The round-insert "button cutter" can bring a high metal removal rate to a low horsepower machining center.

By Michael Bitner
Product Manager, Dapra Corp.

This article originally appeared in Modern Machine Shop magazine.

The work of indexable milling tools is often accompanied by vibration that is a familiar sound – and a familiar feel – in many shops. When these tools are run at heavy depths of cut to achieve high metal removal rates, the productivity may come at the expense of the corner of the cutting tool and the life span of the machine.

One alternative that can provide a smoother cut, in addition to many expanded capabilities, is the copy mill. "Button cutter" is another name for this type of tool.

The copy mill is a simple variation on the traditional end mill, in that the copy mill uses circular insert geometry as opposed to traditional parallelogram or square inserts. This difference delivers a variety of benefits, most of which complement today's trend toward lighter depths of cut and faster feed rates, or high speed machining. This article discusses each of these benefits individually.

Copy milling: a typical pocket roughing routine

A 6" by 12" pocket, 1.25" deep, was cut on a 15 hp, 40 taper machining center using the copy milling cutter shown. Parameters were 2,200 rpm, 250 ipm and 0.035" depth. Cycle time was 8 minutes, 18 seconds.


Some copy mills possess the ability to plunge directly into the material, similar to a drill. This is particularly true of the end mill version of the copy mill, but only where the manufacturer has built in sufficient clearance on the bottom of the tool to permit cutting in this direction. Direct plunging is also possible with a shell mill version of the tool, but most shops would find this to be such a large horsepower drain that they would be better off ramping.

A copy mill can't take the place of a drill; the surface area engaged is too large to continue this way much beyond the desired depth of cut for milling. However, the ability to plunge during milling removes a common machining headache: the need to drill a start hole prior to roughing.

A conventional indexable end mill requires this drilled start hole because the tool is not able to execute a straight Z-axis move into the material. The only other way to enter the material with this type of cutter is a ramp-in entry, which typically calls for CAM software. However, with a copy mill, this step can be avoided. Plunging can be programmed into the control's canned pocketing cycle without concern for the tool's entry. This freedom to plunge is particularly helpful in more complex cavity roughing or surface roughing routines, where a CAM package may interject numerous plunge points in order to complete the roughing tool path. With copy mill cutting tools, these plunge points are no longer a concern.

Helical interpolation with a 1-inch dia. button cutter.

The 4" dia. hole shown here was machined in 4140 steel using a 1" diameter copy mill at 4,000 rpm, 200 ipm and 0.035" depth of cut.

Helical Interpolation

Larger-diameter hole making can be quick and easy when a copy mill is used in combination with helical interpolation. This technique resembles thread milling in that all three axes (X, Y and Z) are in motion simultaneously. It differs from thread milling in that the tool is introduced into the material without a start hole of any kind. The tool simply is positioned at the inside diameter of the hole to begin its helix from there, achieving complete material removal from the hole by ramping down to the final depth.

This smooth operation tends to avoid the high horsepower consumption characteristic of large-diameter hole making. And with the high clearance angles of copy mill cutting tools, ramp angles during helical interpolation can be aggressive, without concern for rubbing the bottom of the cutting edge. The quick and easy process offers the added advantage of allowing many different hole sizes to be generated with the same diameter tool. Hole size variation is all in the programming.

A representative comparison illustrates the potential efficiency improvement from this technique. (See shaded box.)

Cycle Time Comparison For Helical Interpolation

A shop might typically use drilling and circular-interpolation end milling to create a large diameter bore. Consider, for example, a 15-horsepower vertical machining center using this approach to machine a 4" diameter hole 3" deep.

The shop pushes an indexable 1.25" diameter drill through the part first, which takes only 1.5 minutes. The next step, requiring much more time, is to run a circular interpolation canned cycle using an indexable 1" diameter end mill. Parameters for this tool are 0.1" depth of cut, 0.7" width of cut, speed 2,300 rpm and feed rate 25 ipm. The total cycle time for circular interpolation is 35 to 45 minutes, so the total cycle time for two tools together can be assumed to be about 45 minutes.

Now consider helical interpolation used to machine the same hole on the same machine. One possible tool would be a 2" diameter shell mill with round inserts. This analysis assumes a 4-flute, 1/2" IC (inscribed circle insert diameter) inserted cutter.

Typical parameters would be 1,500 rpm and 61 ipm, with a 0.06" helix executed each time the tool interpolates the 4" diameter. At 0.06" per revolution, about 50 passes would be needed to break through the hole, plus 5 more passes to reach the center line of the round insert.

The diameter of each pass equals the difference between the 4" hole diameter and the 2" tool diameter, or 2". Total distance traveled by the tool equals the product of 55 passes multiplied by 6.28" per pass (the circumference of a 2" diameter circle), or 345". At 61 ipm, the time to feed this distance is about 5.5 minutes.

In other words, helical interpolation in this example delivers an 87 percent reduction in cycle time. It also eliminates one tool.

Click here for a detailed article on helical interpolation.

Edge Strength

With no corners to break, a round insert provides the strongest cutting edge available in an indexable carbide insert. The strength comes in handy when operating in a heavy cut, or when attempting roughing cuts under unstable conditions. When cutting with a long-reach tool, the round inserts are more forgiving of tool deflection and chatter, allowing speed and feed rate to be increased with less danger of insert chipping.

Cutting forces are also distributed more effectively. With a typical 90-degree cutting tool, the majority of the tool pressure is radial, resulting in high deflection and increased potential for chatter or breakage. The round cutting edge spreads the force more evenly, directing a larger percentage of the tool pressure into the axial direction. This too is desirable when cutting with longer-length tools, because the reduced radial pressure reduces deflection.

But beware of this condition when using a horizontal machining center. The increased axial pressure may cause flexing in the workholding, which typically is mounted on a tombstone or angle plate that isn't as well supported as the solid base of a vertical machining center. On an HMC, this flexing can result in micro chipping of the insert from the subtle vibrations that occur with the flex. Tool life will be shortened, and cutter breakage is more likely. To reduce or eliminate this problem, try positive axial rake cutters, which minimize the downward push into the workpiece.

Number Of Edges

Round inserts provide the additional benefit of offering a larger number of usable edges than typical carbide inserts. Depending on the size of the insert and the depth of cut, a round insert can provide from four to eight effective indexes, yielding at least twice the total material removal and minutes in the cut of a typical parallelogram or square. This advantage translates to fewer trips to the tool crib for new inserts (keeping the operator at the machine and the tool in the cut), fewer inserts to stock in inventory (lowering on-hand inventory costs) and a lower cost per cutting edge.

For example, the typical parallelogram insert costs about $8. With two usable edges, the cost per edge is $4. A square insert (which usually does not perform as well as a parallelogram because of the lack of a positive topography and axial relief) may cost $10. This comes to $2.50 per edge.

Compare these costs to that of a typical round insert. This insert may cost as much as $11 (many are less). At this cost, the worst-case scenario – heavy cutting permitting only 4 indexes — yields a cost per edge of $2.75. The more typical scenario, 8 indexes, yields a cost per edge of $1.38. These costs, particularly in applications where the round insert delivers more metal removal per minute than other inserts, make the economics of the tool attractive.

Metal Removal With Low Horsepower

Applied correctly, round inserts can yield impressive material removal rates without a demand for impressive horsepower. The strength of a round insert permits feed rates that would not be possible with 90-degree cutting tools, allowing even lighter-duty machines to perform aggressive roughing. The key point to understand with a round insert used in this way is that heavier depths of cut lead to higher chip thickness, which increases horsepower consumption. (See Figure 1.) By taking light cuts – 0.025" to 0.050" depth of cut – the typical round-insert cutting tool can feed at rates in steel around 0.040 inch per tooth, and in certain cases as high as 0.060 inch per tooth. By comparison, most parallelogram or square inserts reach their limit at 0.010 to 0.012 ipt.

It is important to note that some users of button cutters have experienced problems with insert movement in the pocket of the cutting tool during cutting, or when the insert is worn. In either of these cases, tool pressure increases and the effectiveness of the insert clamping can be compromised. The cutter should include design characteristics that strengthen tool integrity for these applications. Some cutters, for example, use screw-through inserts accompanied by extra top clamps. These cutters provide the security of double clamping for each insert.

Another important feature is positive locking in the insert seat. Many button cutters use inexpensive molded inserts that have round sides, providing no radial locking for the insert. Tangential cutting forces on an insert such as this may cause the insert screw to lose torque. More rigid copy mills address this problem with locking surfaces on the sides of the inserts — locating flats that mate with matching flats on the cutter body, leaving little chance for movement.

Finally, look for tools providing maximum support for the cutting edge, particularly if high feed rate is the goal. Copy mill cutters using negative axial rake (tipping the insert down toward the workpiece) can cut well using conservative parameters but fall short during more aggressive metal removal. Inherent in the design is a lack of support for the primary area of force, which is right at the cutting edge. (See Figure 2.) Copy mill cutters using positive axial rake provide much better cutting edge support because the carbide behind the cutting edge is closer to being parallel with the cut. Positioning the carbide in this way lets the end user take advantage of the carbide's ability to absorb high compressive forces.

But in this scenario, toolholding rigidity is important. Stub-length end mill holders or shell mill holders are highly recommended.

With the right tooling, even machine tools with only 10 or 15 hp are capable of competitive metal removal, resulting in fewer setups and greater flexibility in shop floor scheduling.

Figure 1

Fig. 1 – Round inserts cut more efficiently at light depths. A light depth of cut decreases the chip thickness and therefore decreases the horsepower demand.

Figure 2

Fig. 2 – Copy mill cutters using positive axial rake provide a smoother cut and better cutting edge support.

The anatomy of a button cutter.

The anatomy of this copy end mill includes the following features: (1) top clamp for secure insert mounting; (2) positive axial rake for supporting the cutting edge; (3) insert facets for positive locking; (4) ground inserts for accuracy in finish cuts; and (5) adjacent inserts to provide plunging capability.

Roughing Closer to Finish Form

The use of a round insert for roughing applications opens up new possibilities in the preparation for semifinish or finish cuts. When roughing with 90-degree cutters, each step down (or each pass during Z-level roughing) leaves a "stair step" behind. The heavier the depth of cut with each pass, the more dramatic this stair-step effect. The resulting uneven surface leads to uneven pressure on the semifinish tool. This shocks the tool and also causes varying deflection, making direct progression from roughing to finishing out of the question. Not only is a semifinish pass required, but multiple finish passes may be needed as well.

Using round inserts dramatically reduces this effect. In place of the steps left by the 90-degree tool, the surface has much smaller "scallops" that are low in height and easier to machine through. This effect is complemented by the fact that round inserts are optimally applied at lighter depths of cut, because the lighter depth makes the scalloping even less dramatic. The stock remaining after roughing is more even, yielding a surface that can be semifinished aggressively, or in some cases can be finished without the semifinish step.

Dapra's Toroid Cutters are suitable for copy milling.

Want to discuss your application?